This boundary condition provides a wall constraint on the turbulent viscosity (i.e. nut) based on the turbulent kinetic energy (i.e. k) and velocity (i.e. U) for atmospheric boundary layer modelling. More...

Inheritance diagram for atmNutWallFunctionFvPatchScalarField:

[legend]

Collaboration diagram for atmNutWallFunctionFvPatchScalarField:

[legend]

Public Member Functions
	TypeName ("atmNutWallFunction")
	Runtime type information. More...

	atmNutWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	atmNutWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	atmNutWallFunctionFvPatchScalarField (const atmNutWallFunctionFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given atmNutWallFunctionFvPatchScalarField onto a new patch. More...

	atmNutWallFunctionFvPatchScalarField (const atmNutWallFunctionFvPatchScalarField &)
	Construct as copy. More...

virtual tmp< fvPatchScalarField >	clone () const
	Construct and return a clone. More...

	atmNutWallFunctionFvPatchScalarField (const atmNutWallFunctionFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

virtual void	autoMap (const fvPatchFieldMapper &)
	Map (and resize as needed) from self given a mapping object. More...

virtual void	rmap (const fvPatchScalarField &, const labelList &)
	Reverse map the given fvPatchField onto this fvPatchField. More...

virtual void	write (Ostream &) const
	Write. More...

Public Member Functions inherited from nutkWallFunctionFvPatchScalarField
	TypeName ("nutkWallFunction")
	Runtime type information. More...

	nutkWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	nutkWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	nutkWallFunctionFvPatchScalarField (const nutkWallFunctionFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given nutkWallFunctionFvPatchScalarField onto a new patch. More...

	nutkWallFunctionFvPatchScalarField (const nutkWallFunctionFvPatchScalarField &)
	Construct as copy. More...

	nutkWallFunctionFvPatchScalarField (const nutkWallFunctionFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< scalarField >	yPlus () const
	Calculate and return the yPlus at the boundary. More...

Public Member Functions inherited from nutWallFunctionFvPatchScalarField
	TypeName ("nutWallFunction")
	Runtime type information. More...

	nutWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	nutWallFunctionFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	nutWallFunctionFvPatchScalarField (const nutWallFunctionFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given nutWallFunctionFvPatchScalarField onto a new patch. More...

	nutWallFunctionFvPatchScalarField (const nutWallFunctionFvPatchScalarField &)
	Construct as copy. More...

	nutWallFunctionFvPatchScalarField (const nutWallFunctionFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

const wallFunctionCoefficients &	wallCoeffs () const noexcept
	Return wallFunctionCoefficients. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

Protected Member Functions
virtual tmp< scalarField >	calcNut () const
	Calculate the turbulent viscosity. More...

void	writeLocalEntries (Ostream &) const
	Write local wall function variables. More...

Protected Member Functions inherited from nutkWallFunctionFvPatchScalarField
void	writeLocalEntries (Ostream &) const
	Write local wall function variables. More...

Protected Member Functions inherited from nutWallFunctionFvPatchScalarField
virtual const volVectorField &	U (const turbulenceModel &turb) const
	Helper to return the velocity field either from the turbulence model (default) or the mesh database. More...

virtual void	checkType ()
	Check the type of the patch. More...

void	writeLocalEntries (Ostream &) const
	Write local wall function variables. More...

Additional Inherited Members
Static Public Member Functions inherited from nutWallFunctionFvPatchScalarField
static const nutWallFunctionFvPatchScalarField &	nutw (const turbulenceModel &turbModel, const label patchi)
	Return the nut patchField for the given wall patch. More...

Protected Attributes inherited from nutWallFunctionFvPatchScalarField
word	UName_
	Name of velocity field. More...

wallFunctionCoefficients	wallCoeffs_
	Wall-function coefficients. More...

Detailed Description

This boundary condition provides a wall constraint on the turbulent viscosity (i.e. nut) based on the turbulent kinetic energy (i.e. k) and velocity (i.e. U) for atmospheric boundary layer modelling.

The governing equation of the boundary condition:

$\tau_w = {U^*_u} {U^*_k}$

with

${U^*_u} = \frac{\kappa U_w}{ln(z_p / z_0)}$

${U^*_k} = C_{\mu}^{1/4} \sqrt{k}$

where

$\tau_w$	=	wall shear stress
	=	local friction velocity based on near-ground velocity
	=	local friction velocity based on near-ground k
$\kappa$	=	von Kármán constant
	=	near-ground velocity
	=	vertical coordinate
	=	surface roughness length [m]
	=	empirical model constant
	=	turbulent kinetic energy

References:

        Theoretical expressions (tags:RH, SBJM, SM):
            Richards, P. J., & Hoxey, R. P. (1993).
            Appropriate boundary conditions for computational wind
            engineering models using the k-ε turbulence model.
            In Computational Wind Engineering 1 (pp. 145-153).
            DOI:10.1016/B978-0-444-81688-7.50018-8

            Sørensen, N. N., Bechmann, A., Johansen, J., Myllerup, L.,
            Botha, P., Vinther, S., & Nielsen, B. S. (2007).
            Identification of severe wind conditions using
            a Reynolds Averaged Navier-Stokes solver.
            In Journal of Physics: Conference
            series (Vol. 75, No. 1, p. 012053).
            DOI:10.1088/1742-6596/75/1/012053

            Sumner, J., & Masson, C. (2012).
            k−ε simulations of the neutral atmospheric boundary layer:
            analysis and correction of discretization errors on practical grids.
            International journal for numerical
            methods in fluids, 70(6), 724-741.
            DOI:10.1002/fld.2709

Required fields:

      nut     | Turbulent viscosity      [m2/s]
      k       | Turbulent kinetic energy [m2/s2]

Usage

Example of the boundary condition specification:

<patchName>
{
    // Mandatory entries
    type            atmNutWallFunction;
    z0Min           <scalar>;
    z0              <PatchFunction1<scalar>>;

    // Inherited entries
    ...
}

where the entries mean:

Property	Description	Type	Reqd	Deflt
`type`	Type name: nutAtmWallFunction	word	yes	-
`z0Min`	Minimum surface roughness length [m]	scalar	yes	-
`z0`	Surface roughness length [m]	PatchFunction1<scalar>	yes	-

The inherited entries are elaborated in:

Source files

Definition at line 200 of file atmNutWallFunctionFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ atmNutWallFunctionFvPatchScalarField() [1/5]

atmNutWallFunctionFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct from patch and internal field.

Definition at line 125 of file atmNutWallFunctionFvPatchScalarField.C.

Referenced by atmNutWallFunctionFvPatchScalarField::clone().

Here is the caller graph for this function:

◆ atmNutWallFunctionFvPatchScalarField() [2/5]

atmNutWallFunctionFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 151 of file atmNutWallFunctionFvPatchScalarField.C.

◆ atmNutWallFunctionFvPatchScalarField() [3/5]

atmNutWallFunctionFvPatchScalarField	(	const atmNutWallFunctionFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given atmNutWallFunctionFvPatchScalarField onto a new patch.

Definition at line 137 of file atmNutWallFunctionFvPatchScalarField.C.

◆ atmNutWallFunctionFvPatchScalarField() [4/5]

atmNutWallFunctionFvPatchScalarField ( const atmNutWallFunctionFvPatchScalarField & rwfpsf )

Construct as copy.

Definition at line 172 of file atmNutWallFunctionFvPatchScalarField.C.

◆ atmNutWallFunctionFvPatchScalarField() [5/5]

atmNutWallFunctionFvPatchScalarField	(	const atmNutWallFunctionFvPatchScalarField &	rwfpsf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct as copy setting internal field reference.

Definition at line 183 of file atmNutWallFunctionFvPatchScalarField.C.

Member Function Documentation

◆ calcNut()

tmp< scalarField > calcNut ( ) const

protectedvirtual

Calculate the turbulent viscosity.

Reimplemented from nutkWallFunctionFvPatchScalarField.

Definition at line 36 of file atmNutWallFunctionFvPatchScalarField.C.

References wallFunctionCoefficients::Cmu(), Foam::exit(), Foam::FatalError, FatalErrorInFunction, forAll, Foam::constant::atomic::group, IOobject::groupName(), k, Foam::constant::electromagnetic::kappa, wallFunctionCoefficients::kappa(), Foam::log(), Foam::mag(), magUp, Foam::max(), tmp< T >::New(), nutWallFunctionFvPatchScalarField::nutw(), Foam::foamVersion::patch, fvPatchField< Type >::patchInternalField(), Foam::pow025(), turbulenceModel::propertiesName, Foam::sqrt(), tauw, nutWallFunctionFvPatchScalarField::wallCoeffs_, and y.

Here is the call graph for this function:

◆ writeLocalEntries()

void writeLocalEntries ( Ostream & os ) const

protected

Write local wall function variables.

Definition at line 109 of file atmNutWallFunctionFvPatchScalarField.C.

References os(), and Ostream::writeEntryIfDifferent().

Referenced by atmNutWallFunctionFvPatchScalarField::write().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ TypeName()

TypeName ( "atmNutWallFunction" )

Runtime type information.

◆ clone() [1/2]

virtual tmp<fvPatchScalarField> clone ( ) const

inlinevirtual

Construct and return a clone.

Reimplemented from nutkWallFunctionFvPatchScalarField.

Definition at line 286 of file atmNutWallFunctionFvPatchScalarField.H.

References atmNutWallFunctionFvPatchScalarField::atmNutWallFunctionFvPatchScalarField().

Here is the call graph for this function:

◆ clone() [2/2]

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Reimplemented from nutkWallFunctionFvPatchScalarField.

Definition at line 307 of file atmNutWallFunctionFvPatchScalarField.H.

References atmNutWallFunctionFvPatchScalarField::atmNutWallFunctionFvPatchScalarField().

Here is the call graph for this function:

◆ autoMap()

void autoMap ( const fvPatchFieldMapper & m )

virtual

Map (and resize as needed) from self given a mapping object.

Definition at line 197 of file atmNutWallFunctionFvPatchScalarField.C.

◆ rmap()

void rmap	(	const fvPatchScalarField &	ptf,
		const labelList &	addr
	)

virtual

Reverse map the given fvPatchField onto this fvPatchField.

Definition at line 211 of file atmNutWallFunctionFvPatchScalarField.C.

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Reimplemented from nutkWallFunctionFvPatchScalarField.

Definition at line 228 of file atmNutWallFunctionFvPatchScalarField.C.

References os(), nutWallFunctionFvPatchScalarField::write(), atmNutWallFunctionFvPatchScalarField::writeLocalEntries(), and fvPatchField< Type >::writeValueEntry().

Here is the call graph for this function:

The documentation for this class was generated from the following files:

src/atmosphericModels/derivedFvPatchFields/wallFunctions/atmNutWallFunction/atmNutWallFunctionFvPatchScalarField.H
src/atmosphericModels/derivedFvPatchFields/wallFunctions/atmNutWallFunction/atmNutWallFunctionFvPatchScalarField.C

Public Member Functions

Protected Member Functions

Additional Inherited Members

Detailed Description

Constructor & Destructor Documentation

◆ atmNutWallFunctionFvPatchScalarField() [1/5]

◆ atmNutWallFunctionFvPatchScalarField() [2/5]

◆ atmNutWallFunctionFvPatchScalarField() [3/5]

◆ atmNutWallFunctionFvPatchScalarField() [4/5]

◆ atmNutWallFunctionFvPatchScalarField() [5/5]

Member Function Documentation

◆ calcNut()

◆ writeLocalEntries()

◆ TypeName()

◆ clone() [1/2]

◆ clone() [2/2]

◆ autoMap()

◆ rmap()

◆ write()